Solidworks 2009 Design with Analysis – Deep Fry Basket PDF

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Solidworks 2009 Design with Analysis – Deep Fry Basket Solidworks 2009 Design with Analysis (Tutorial 3 – Deep Fry Basket) Infrastructure Sketcher Solid-modeling Surface-modeling Assembly Design Structural Analysis A- 1 Version 2a – June 2010 Non-Commercial Use Written by Dickson Sham Solidworks 200...

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Solidworks 2009 Design with Analysis – Deep Fry Basket

Solidworks 2009 Design with Analysis (Tutorial 3 – Deep Fry Basket)

Infrastructure Sketcher Solid-modeling Surface-modeling Assembly Design Structural Analysis A- 1 Version 2a – June 2010

Non-Commercial Use

Written by Dickson Sham

Solidworks 2009 Design with Analysis – Deep Fry Basket

Overview of Tasks

Tutorial 3A - Modeling • Build a Master Model of the basket handle • Create the upper & the lower parts from the Master Model • Build the mechanical features on the both parts • Get the both parts auto-updated after modifying the outlook of the master model Parts

Tutorial 3B - Modeling • Build the metal arm • Build the basket • Add material texture onto all components • Assemble components

Master Model

Linked Children

Assembly

Tutorial 3C – Structural analysis • Simplify the model for analysis • Create Meshes onto two components and create connectors between them • Create boundary conditions & define properties • Analyze displacements & stresses Tutorial 3D – Structural analysis (By Nastran) • Repeat Tutorial 3C with the use of Nastran A- 2 Version 2a – June 2010

Non-Commercial Use

Structural analysis Written by Dickson Sham

Solidworks 2009 Design with Analysis – Deep Fry Basket

General

Change the view with the mouse A.

Rotating enables you to rotate the model around a point. Click and hold the middle mouse button, then drag the mouse.

B.

Panning enables you to move the model on a plane parallel to the screen. Press and hold “Ctrl” key, then click and hold the middle mouse button, then drag the mouse.

C.

Zooming enables you to increase or decrease the size of the model. Press and hold “Shift” key, then click and hold the middle button, then drag the mouse up or down.

Middle button

A- 3 Version 2a – June 2010

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A Not For Commercial Use

• • • •

Enter Solidworks 2009 Select “File/New” on the menu bar; Select “Part” Click OK

•

Select “View/Origins” on the top menu to show the system origin (blue)

To build 1st sketch:• Click “Sketch” icon and select Top Plane • Draw an arc with one end touching y-axis • Add a dimension onto the circle by clicking “Smart Dimension” icon and then selecting the circle. • Modify the radius as 380mm; the arc will be resized automatically • Draw a centerline along the x-axis • Click “Mirror Entities” icon and then select the arc and the centerline (mirror about) to duplicate the arc on the opposite side

origin

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Non-Commercial Use

Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

To build • •

• • • •

1st

sketch (Cont’):-

Tutorial 3A

Draw an Arc

Draw an arc (R35) connecting the bigger arcs, on the positive-x side, which is NOT tangent to them Similarly, Draw another smaller arc (R10) connecting the bigger arcs on the negative-x side Multi-select the arc (R10) and the upper arc(R380) by pressing and holding “ctrl” key on the keyboard Select “Tangent” in the entry box “Add Relations” Click Ok Add another “Tangent” relation between the arc (R10) and the lower arc(R380) by repeating the above steps Not Tangent Tangent

Tangent

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Not Tangent Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

To build • •

• • • •

1st

sketch (Cont’):-

Tutorial 3A

Click “Smart Dimension” icon and then select the arcs R10 & R35 (by default, distance is measured from two arc centers) Select the tabpage “Leaders” Select “Max” for First arc condition & Second arc condition Modify the value to 120mm

•

Similarly, Click “Smart Dimension” icon and then select the endpoints of arc R35 Modify the value to 36mm

•

Exit the workbench by clicking “Exit Sketch” icon

•

Now, you are back to the 3D environment and “Sketch1” is created on the tree. A- 6

Version 2a – June 2010

Non-Commercial Use

Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To build a solid:• •

Click “Extruded Boss/Base” icon Select “Sketch1” on the tree / click on the profile directly

• • • •

(Select “Blind” as type) Enter 20mm as the length of Direction 1 Click ok A solid is created

To round the sharp edges:•

Add a “Fillet” R5mm onto the vertical sharp edges

R5

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R5 Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To make a draft on the solid:• •

Draft +1deg

Click “Draft ” icon Enter 1deg as Angle

•

Select the bottom face as “Neutral plane”

•

The arrow should point UPWARD. If not, click it to reverse.

•

Move the mouse cursor onto a vertical face , then right-click and select “Select Tangency” (all tangent faces are selected as “Faces to Draft” )

•

Click ok to complete

Bottom face is Neutral Plane

Vertical faces (Faces to draft)

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To make a mirror solid:• •

Click “Mirror” icon Select the bottom face as “Mirror Plane”

• •

Click on the entry box “Bodies to Mirror” Select the solid

•

Click ok to complete

Result

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To create a reference plane:•

Click “Plane” icon

• • •

Select “Right Plane” on tree Enter 38mm as Offset value Select the option “Reverse direction”

•

Click ok to complete

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To build 2nd sketch:• •

• • • • •

Click “Sketch” icon and select Front Plane Press “Space” key on the keyboard and then select “Normal to” Draw a horizontal centerline as shown Multi-select the endpoint of the centerline and plane1 by pressing and holding “ctrl” key on the keyboard Select “Coincident” and “ok” Add a dimension 12mm

•

Draw another two arcs (R450 & R270) and add the two tangent relations as shown Exit the workbench by clicking “Exit Sketch” icon

•

Click on an empty space to deselect the sketch

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Centerline Tangent & coincided

Plane1

Origin

Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

To build

3rd

sketch:-

Tutorial 3A

• •

Click “Sketch” icon and select Plane1 Press “Space” key on the keyboard and then select “Normal to”

• • •

Draw a centerline along y-axis Draw an arc as shown Multi-select the endpoints of the arc, then the centerline by pressing and holding “ctrl” key on the keyboard Select “Symmetric” and “ok”

• • • • • • •

Sketch.2

Add Dimension R30 onto the arc Rotate the model by mouse to have an isometric view Multi-select the arc and the point by pressing and holding “ctrl” key on the keyboard. Select “Coincident” and “ok” (Now the arc should be coincided with Sketch.2) Exit sketch

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To build a Surface:• • • • •

Select “Insert/Surface/Sweep” on the top menu bar Select “Sketch2” as Profile Select “Sketch3” as Path Click ok (A surface is created, which is stored in another folder named as “Surface Bodies” on the tree) Sketch.2

profile path

Sketch.3

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To duplicate a surface by mirroring:• • • • • •

Not For Commercial Use

Click “Mirror” icon Select Front Plane as “Mirror Plane” Select “Surface-Sweep1” as “Bodies to Mirror” Select “Knit Surfaces” under “Options” Click ok to complete (The original surface and the mirror surface are knitted together as one big surface, which is stored in the folder named as “Surface Bodies” on the tree)

Only one resultant surface

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To cut the solid with a surface:• • • •

Select “Insert/Cut/With Surface” on the menu bar Select the surface Reverse the arrow so that it points upward Click ok to complete

To hide the surface:• •

Right-Click on the surface Select icon “Hide”

Or click on arrow to change

Click this icon to change arrow direction

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A Now, we are going to create a Loft surface for the bottom face. Before that, we need to construct three guide curves and three different profiles

Guide-curve Guide-curve

Profile

Guide-curve

To create a reference plane:• • • • •

Click “Plane” icon Select “Top Plane” on tree Enter 2mm as Offset value Select the option “Reverse direction” Click ok

Profile Profile

the new plane

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To create an intersection curve:• Select “Insert/Curve/Split Line…” on the menu bar • Select “Intersection” as “Type of Split” • Select Plane2 as “splitting plane” • Select the Face as “Face to Split” • Click ok to complete Plane2 To create another intersection curve on the opposite side:• Repeat the above steps but select the Face as “Face to Split”

Split Line.1

Remark: The selected faces will be broken into two Version 2a – June 2010

Split Line.2

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To build 4th sketch:• •

Click “Sketch” icon and select Front Plane Press “Space” key on the keyboard and then select “Normal to”

•

Draw a horizontal centerline as shown (with one endpoint touching Plane1, 15mm below the origin)

•

Draw another two arcs (R300 & R150) by using “Tangent arc” command. (Two tangent relations are created automatically)

•

•

“Exit Sketch”

•

Click on an empty space to deselect the sketch A- 18

Version 2a – June 2010

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Tangent & coincided Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To build 5th sketch:• •

Click “Sketch” icon and select Plane1 Press Space key on the keyboard and then select “Normal to”

•

Draw an arc as shown

•

Rotate the model so that you can see the edges “Split Line1” & “Split Line2”

•

Multi-select an endpoint of the arc and “Split Line1”, then select “Pierce”

•

Similarly, multi-select the other endpoint of the arc and “Split Line2”, then select “Pierce”

Split Line 1

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To build 5th sketch (Cont’):•

• • •

Multi-select the arc and the point of Sketch4 by pressing and holding “ctrl” key on the keyboard. Select “Coincident” and “ok”. (The arc now touches “Split Line1”, “Split Line2”, & “Sketch4”) “Exit Sketch”

point Sketch4

To create a reference plane:• • • •

Click “Plane” icon Select “Right Plane” Select Endpoint of the edge “Split Line1” Click ok

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Split Line1

Make a plane at the endpoint of “Split Line 1“ Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To build 6th sketch:•

Click “Sketch” icon and select Plane.3

•

Draw an arc with the endpoints “Split Line1” & “Split Line2”

• • • •

touching Split Line2

Draw a point on the arc Multi-select the point and Sketch4, then select “Pierce” (The arc now touches Sketch4, too) “Exit Sketch” Split Line1

Draw an arc touching “Split Line1” & “Split Line2”

Sketch.4

The resultant arc touches “Split Line1”, “Split Line2”, and also “Sketch4” A- 21 Version 2a – June 2010

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To create a reference plane:• • • •

Click “Plane” icon Select “Right Plane” Select another Endpoint Line.1” Click ok to complete

of the curve “Split

To build 7th sketch:•

Draw an Arc, which touches “Split Line1”, “Split Line2” & “Sketch4”

•

(Refer to the steps of building 6th sketch)

•

Exit Sketch

Sketch4

Split Line1 A- 22 Version 2a – June 2010

Split Line2

Non-Commercial Use

Draw an arc touching three curves Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To create a Loft surface:• •

•

Sketch.4 Sketch.7 (guide) (profile)

Select “Insert/Surface/Loft..” on the menu bar Select “Sketch.6”, “Sketch.5”, & “Sketch.7” in order (They will then be inserted into the entry box of Profiles) All closing points (Blue points) should be on the same side; If not, drag on it to change.

• •

Then click the entry box of Guide Curves once Select “Split Line.1”, “Sketch.4” & “Split Line.2”

•

Click ok to complete

Split Line2 (guide)

Sketch.5 (profile)

Split Line1 (guide) Sketch.6 (profile) All blue points should be on the same side, otherwise the resultant surface will be twisted

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A

Hide the solid

As seen, the Loft surface is not big enough to cut through the whole solid… To hide the solid:• •

Right-click on the solid Select “Hide”

*Hide all Planes (Plane1, 2, 3 & 4)*

To extend the surface from both ends:• • • • •

Select “Insert/ Surface/ Extend…” on the top menu bar Select the two edges Enter 20mm as Length D1 Select “Same Surface” as “Extension Type” Click ok to complete

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To Unhide the solid body:• Right-Click “Split Line2” on tree • Select icon “Show”

Show the solid

To cut the solid with this extended surface:• Select “Insert/ Cut/ With Surface” on the top menu bar • Select the extended surface • Reverse the arrow so that it points downward. • Click ok to complete

To hide the surface:• Right-Click the surface, then select “Hide”

Result after split by the extended surface

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A Next, we are going to create a curve-based pocket on the top face:-

Not For Commercial Use To create a reference plane (plane.5):• • • • •

Click “Plane” icon Select “Right Plane” Enter 23mm as Offset value Click “Reverse Direction” Click ok

Create a plane

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Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To build 8th sketch:• • • • • •

Click “Sketch” icon and select plane.5 Draw a centerline along y-axis Draw an arc (R24, endpoints symmetric about the centerline) Add a Dimension (9mm) to define the distance between the arc and the origin “Exit Sketch” Click on an empty space to deselect the sketch

To build 9th sketch:• • • • • •

Click “Sketch” icon and select Front Plane Draw a centerline onto the centerline of Sketch8 Draw an arc (R28, endpoints symmetric about the centerline) Add a Dimension (9mm) to define the distance between the arc and the origin “Exit Sketch” Click on an empty space to deselect the sketch A- 27

Version 2a – June 2010

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Draw a centerline Written by Dickson Sham

Modeling

Solidworks 2009 Design with Analysis – Deep Fry Basket

Tutorial 3A To build a Sweep Surface:• Select “Insert/Surface/Sweep” on the menu bar • Select “Sketch9” as Profile • Select “Sketch8” as Path • Click ok

Sweep.2

To duplicate a surface by mirroring:• Click “Mirror” icon • Select “Front Plane” as “Mirror Plane” • Select “Surface-Sweep2” as “Bodies to Mirror” • Select “Knit Surfaces” under “Options” • Click ok To cut the solid with this SURFACE:• Select “Insert/Cut/With Surface” on the top menu bar • Select the surface • (arrow should point ...